ANSYS数据导出举例

！get,nodenum,node,,num,max ! 获得节点的数目

*dim,nodepos,array,nodenum,3 ! nodepos存放节点的坐标*do,i,1,nodenum,1

*get,nodepos(i,1),node,i,loc,x !获得节点的X坐标

*get,nodepos(i,2),node,i,loc,y

*get,nodepos(i,3),node,i,loc,z

*enddo

*get,elemnum,elem,,num,max !得到单元的总数目
*dim,elemlist,array,elemnum,6 !单元包含的节点列表，指定每个单元包含6个节点，根据情况修改

*do,i,1,elemnum,1
*do,ii,1,6,1
*get,elemlist(i,ii),elem,i,node,ii !获得节点编号
*enddo
*enddo

*cfopen,geomfile,txt !打开文件，写入数据
*vwrite,0
(F8.0,' Coordinates of each node')
*vwrite,sequ,nodepos(1,1),nodepos(1,2),nodepos(1,3)
(F8.0,3e16.8)

*vwrite,0
(F8.0,' Nodes No. of each element')

*vwrite,sequ,elemlist(1,1),elemlist(1,2),elemlist(1,3),elemlist(1,4),elemlist(1,5),elemlist(1,6)
(F8.0,6f8.0)

*vwrite,0
(F8.0)
*cfclos

! 提取振型

*get,nodenum,node,,num,max

*set,tempvar,0
*set,modenum,0

!获得模态的阶数
*do,i,1,100,1
*get,tempvar,mode,i,freq
*if,tempvar,LT,0.0001,THEN
*if,modenum,LT,0.0001,THEN
*set,modenum,(i-1)
*endif
*endif
*enddo

!*dim,modefqda,array,modenum,2
*dim,modeshp,array,nodenum,3

*cfopen,modefile,txt

*do,i,1,modenum,1
*get,modefq,mode,i,freq
*get,modeda,mode,i,damp
*vwrite,modefq,modeda
(2e16.8)

set,1,i
!获得每个节点的位移
*do,ii,1,nodenum,1
*get,modeshp(ii,1),node,ii,u,x
*get,modeshp(ii,2),node,ii,u,y
*get,modeshp(ii,3),node,ii,u,z
*enddo

*vwrite,sequ,modeshp(1,1),modeshp(1,2),modeshp(1,3)
(F8.0,3e16.8)
*vwrite,0
(F8.0)
*enddo

*cfclos